Abaqus generates diagnostic information during an analysis job; Abaqus/CAE reads the diagnostic information that is stored in the output database. Thus, you can use the Job Diagnostics dialog box to view convergence information only for procedures that generate information in the output database. Job diagnostics are stored in the output database for the following Abaqus/Standard procedures:

• Coupled temp-displacement

• Geostatic

• Soils

• Static, General

• Static, Linear perturbation

• Static, Riks

• Visco

Diagnostic information for other Abaqus/Standard analysis procedures is located in the message file and cannot be viewed in Abaqus/CAE.

Diagnostic information is available in Abaqus/CAE for all Abaqus/Explicit analysis procedures. An anneal procedure does not generate any diagnostic data, so no diagnostics are displayed for an anneal step.

Detailed diagnostic information is saved to the output database by default for the supported analysis procedures in both Abaqus/Standard and Abaqus/Explicit. If you do not want to include diagnostic information, use the Keywords Editor to edit the input file to include the following line in the model data:

*OUTPUT, DIAGNOSTICS=NO

You can also use the Keywords Editor to change the default diagnostic output parameters for Abaqus/Explicit by including one or more lines for the keyword *DIAGNOSTICS and specifying the desired parameter values.

For more information on using the Keywords Editor, see “Adding unsupported keywords to your Abaqus/CAE model,” Section 9.10.1.