Abaqus Keywords Reference Guide  
How to find keyword examples

*CONCRETE DAMAGED PLASTICITY
Define flow potential, yield surface, and viscosity parameters for the concrete damaged plasticity model.

This option is used to define flow potential, yield surface, and viscosity parameters for the concrete damaged plasticity material model. The *CONCRETE DAMAGED PLASTICITY option must be used in conjunction with the *CONCRETE TENSION STIFFENING and the *CONCRETE COMPRESSION HARDENING options. In addition, the *CONCRETE TENSION DAMAGE and/or the *CONCRETE COMPRESSION DAMAGE options can be used to specify tensile and/or compressive stiffness degradation damage.

Products: Abaqus/Standard  Abaqus/Explicit  Abaqus/CAE  

Type: Model data

Level: Model  

Abaqus/CAE: Property module

References:

Optional parameter:

DEPENDENCIES

Set this parameter equal to the number of field variable dependencies included in the definition of the material parameters other than temperature. If this parameter is omitted, it is assumed that the material parameters depend only on temperature. See “Specifying field variable dependence” in “Material data definition,” Section 21.1.2 of the Abaqus Analysis User's Guide, for more information.

Data lines to define concrete damaged plasticity flow potential, yield surface, and viscosity parameters: 

First line:

  1. Dilation angle, , in the p–q plane. Give the value in degrees.

  2. Flow potential eccentricity, . The eccentricity is a small positive number that defines the rate at which the hyperbolic flow potential approaches its asymptote. If this field is left blank or a value of 0.0 is entered, the default of is used.

  3. , the ratio of initial equibiaxial compressive yield stress to initial uniaxial compressive yield stress. If this field is left blank or a value of 0.0 is entered, the default of is used.

  4. , the ratio of the second stress invariant on the tensile meridian, , to that on the compressive meridian, , at initial yield for any given value of the pressure invariant p such that the maximum principal stress is negative, . It must satisfy the condition . If this field is left blank or a value of 0.0 is entered, the default of is used.

  5. Viscosity parameter, , used for the visco-plastic regularization of the concrete constitutive equations in Abaqus/Standard analyses. This parameter is ignored in Abaqus/Explicit. The default value is . (Units of .)

  6. Temperature.

  7. First field variable.

  8. Second field variable.

Subsequent lines (only needed if the DEPENDENCIES parameter has a value greater than two):

  1. Third field variable.

  2. Etc., up to eight field variables per line.

Repeat this set of data lines as often as necessary to define the dependence of the material parameters on temperature and other predefined field variables.